Create Profile Center Mate (DriveWorks Documentation)

Create Profile Center Mate

The Create Profile Center Mate Generation Task will create a Profile Center Mate, in an Assembly, between named Faces in each Component.

This Generation Task does require named faces to exist in the models being mated. Edges or Planes cannot be used.

See How to Name and Write Rules for a Face or Plane in a SOLIDWORKS Part for more information about Naming and Writing Rules.

Properties

Property Name	Description
(Name)	The unique name for this task.
Aligned	The alignment type (True = Aligned, False = Anti-Aligned).
Distance	The distance between the two faces (in model units).
Flip	Flip the distance (TRUE = Flipped, FALSE = Not Flipped). The default is FALSE.
Lock Rotation	Only applies to circular faces (TRUE = Locked, FALSE = Not Locked). The default is FALSE.
First Face	The name of the first reference mating face.
Second Face	The name of the second reference mating face.

Example

When this task is added the properties are both static and dynamic by default. See How To: Change A Static Property To A Dynamic Property to enable rules to be built on these properties.

Property Name	Example Rule	Example Result	Meaning
Aligned	FALSE	FALSE	FALSE will mean the mate type is Anti-Aligned. TRUE would make the mate Aligned.
Distance	0	0	This is the Distance between the two mating Faces. This is measured in the Model units.
Flip	TRUE	TRUE	This will flip the direction in which the dimension value will be enacted.
Lock Rotation	TRUE	TRUE	TRUE will Lock the Rotation of Cylindrical parts that are inserted with the mate.
First Face	"BaseMountingFace@Base " &DWSpecificationId&"-1"	BaseMountingFace@Base 9999-1	The Name of the First Reference Mating Face.
Second Face	"CoverFace@Cover " &DWSpecificationId&"-1"	CoverFace@Cover 9999-1	The Name of the Second Reference Mating Face.

Rules for Face Names

When building the rule for the Face Names, they must reference the generated file name and not the master. The rule must be built in the form: [Face Name]@[Generated model name]-[Instance number].

If the Face is in the top level assembly, only the Face name is required.

The rule must include the instance number, even if there is only one instance of the component in the assembly.

Face Names can be multiple levels deep. For example, the rule:

[Face or Plane Name]@[Generated model name]-[Instance number]@[Generated sub sub assembly name]-[Instance number]@[Generated sub assembly name]-[Instance number]

would be valid.

To determine the exact address of the Mate Selections:

Manually mate the same entities in SOLIDWORKS and note the addresses given in the Mate Selections window.

When filling out the Entity Names it is important to remember to add a space after the end of your model name before your quote otherwise the Task will not work. For example "Part "&DWSpecificationId .

For more information about Mate Alignment see Mate Alignment in the SOLIDWORKS Help file.

Generation Sequence

This Task can be added to the following Generation Sequence(s):

Pre Drive (will be run before the Main Drive Sequence)
Post Drive (will be run after the Main Drive Sequence)

DriveWorks Tech Tips Portal

Insert Component Generation Task

This project demonstrates how to insert and define a component using Generation Tasks, and also how to use Looping to insert multiple components.

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DriveWorks Pro 22 Create Profile Center Mate