DriveWorks Pro 17: Sheet Metal Features [send feedback...]

Sheet Metal Features

This document describes the types of rules that can be applied to models that have advanced feature parameters captured.

Driving advanced feature dimensions increases model generation time. Where possible capture feature dimensions (distances, numbers and angles) as dimensions rather than an advanced feature parameter.

During model generation captured dimensions are driven before captured advanced feature parameters. If the advanced feature parameter has also been captured as a dimension the value being driven into the advanced feature parameter will override the captured dimension.

Sheet Metal

Edge Flange

SOLIDWORKS ParameterDriveWorks Advanced Feature ParameterRule ResultNotes
Flange Parameters
Use Default RadiusUse Default Bend RadiusOne of the following values:

TRUE

FALSE

Bend RadiusBend RadiusA number representing the radius of the bend, for example:

0.1

This will only be driven when Use Default Bend Radius is FALSE and a sheet metal gauge table is not in use.
Gap DistanceGap DistanceA number representing the distance for the gap, for example:

1

This will only be driven when two or more adjacent edges exist.
Angle
Flange AngleBend AngleA number representing the angle of the edge flange, for example:

90

Flange Length
Reverse DirectionReverse OffsetOne of the following values:

TRUE

FALSE

LengthOffset DistanceA number representing the length, for example:

25

TypeOffset Dim TypeOne of the following numbers:
  • 1 - to use Outer Virtual Sharp
  • 2 - to use Inner Virtual Sharp
  • 3 - to use Tangent Bend
Tangent Bend will only be driven when Bend Angle is equal to or greater than 90°.
Flange Position
PositionPosition TypeOne of the following numbers:
  • 1 - to use Material Inside
  • 2 - to use Material Outside
  • 3 - to use Bend Outside
  • 4 - has no effect
  • 5 - to use Bend from Virtual Sharp
  • 6 - to use Tangent to Bend
Trim Side BendsUse Position Trim Side BendsOne of the following values:

TRUE

FALSE

OffsetUse Position OffsetOne of the following values:

TRUE

FALSE

Reverse DirectionReverse Position OffsetOne of the following values:

TRUE

FALSE

This will only be driven when Use Position Offset is TRUE.
Offset End ConditionOffset TypeOnly Blind can be driven. This will only be driven when Use Position Offset is TRUE.

Blind is the only condition that can be driven.

Offset DistancePosition Offset DistanceA number representing the distance of the offset, for example:

2

This will only be driven when Offset Type is Blind.
Relief
Custom Relief TypeUse Default Bend ReliefOne of the following values:

TRUE - to use the default bend relief

FALSE - to use custom relief type

Relief TypeAuto Relief TypeOne of the following numbers:
  • 1 - to use Rectangle
  • 2 - to use Tear
  • 3 - to use Obround
This will only be driven when Use Default Bend Relief is TRUE.
WidthRelief WidthA number representing the width, for example:

2

This will only be driven when Auto Relief Type is SheetMetalReliefObround or SheetMetalReliefRectangle and Use Relief Ratio is FALSE.
DepthRelief DepthA number representing the depth, for example:

2

This will only be driven when AutoReliefType is SheetMetalReliefObround or SheetMetalReliefRectangle and UseReliefRatio is FALSE.
TearRelief Tear TypeOne of the following numbers:
  • 1 - to use Rip
  • 2 - to use Extend
This will only be driven when Auto Relief Type is SheetMetalReliefTear.
Use relief ratioUse Relief RatioOne of the following values:

TRUE

FALSE

RatioRelief RatioA number representing the ratio, for example:

0.05

This will only be driven when Auto Relief Type is SheetMetalReliefObround or SheetMetalReliefRectangle and Use Relief Ratio is TRUE.

Hem

SOLIDWORKS ParameterDriveWorks Advanced Feature ParameterRule ResultNotes
Edges
PositionBendPositionOne of the following values:

swHemPositionTypeInside

swHemPositionTypeOutside

Type and Size
TypeBendType
LengthLengthA number representing the length, for example:

20

Will only be driven when the Hem type is Closed or Open.
GapDistanceGapDistanceA number representing the distance, for example:

5

Will only be driven when the Hem type is Open.
AngleAngleA number representing the distance, for example:

225

Will only be driven when the Hem type is Tear Drop or Rolled.
RadiusRadiusA number representing the radius, for example:

0.5

Will only be driven when the Hem type is Tear Drop or Rolled.
Miter Gap
Miter GapMiterGapA number representing the gap, for example:

1

This will be driven when there are intersecting hems.
Custom Bend Allowance
K-FactorKFactorA number representing the K-Factor, for example:

0.1

Custom Bend Allowance must be checked and Bend Allowance Type set to K-Factor in the master model.
Bend TableBendTableFileThe name of the table to use, for example:

BASE BEND TABLE

Custom Bend Allowance must be checked and Bend Allowance Type set to Bend Table in the master model.
Bend AllowanceBendAllowanceA number representing the Bend Allowance, for example:

-0.1

Custom Bend Allowance must be checked and Bend Allowance Type set to Bend Allowance in the master model.
Bend DeductionBendDeductionA number representing the Bend Deduction, for example:

-0.1

Custom Bend Allowance must be checked and Bend Allowance Type set to Bend Deduction in the master model.
Custom Relief Type
Advanced Parameters cannot be driven for custom relief type.

Base Flange

SOLIDWORKS ParameterDriveWorks Advanced Feature ParameterRule ResultNotes
Direction 1
Direction 2
Sheet Metal Gauges
Sheet Metal Parameters
Bend Allowance
Auto Relief
ParameterTypeDescription
OverrideThicknessTrue/FalseSets whether to override the thickness value specified in the gauge table for this base flange feature.
ThicknessDistanceSets the thickness for this base flange feature
OverrideRadiusTrue/FalseSets whether to override the bend radius value specified in the gauge table for this base flange feature.
BendRadiusDistanceControls the bend radius for the Base Flange feature.
ReverseDirectionTrue/FalseSets whether to Reverse the Direction.
ReverseThicknessTrue/FalseSets whether to Reverse the Thickness.
OffsetDirections

One of the following values:

OneDirection

TwoDirections

Either "OneDirection" for one direction, or "TwoDirections" for two.
D1OffsetDistanceDistanceBase Flange direction 1 offset Type.
D2OffsetDistanceDistanceBase Flange direction 2 offset Type.

Bends

ParameterTypeDescription
BendRadiusDistanceControls the bend radius for a sheet metal feature.
BendDeductionDistance
BendAllowanceDistance
KFactorNumber
Type

One of the following values:

BendAllowBendTable

BendAlllowKFactor

BendAllowance

BendDeduction

ReliefRatioNumberControls the sheet metal relief ratio.

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