Sheet Metal Features (DriveWorks Documentation)

Sheet Metal Features

This document describes the types of rules that can be applied to models that have advanced feature parameters captured.

Driving advanced feature dimensions increases model generation time. Where possible capture feature dimensions (distances, numbers and angles) as dimensions rather than an advanced feature parameter.

During model generation captured dimensions are driven before captured advanced feature parameters. If the advanced feature parameter has also been captured as a dimension the value being driven into the advanced feature parameter will override the captured dimension.

Bend Table

Parameter	Input Type	Description
Bend Table File Path	Path	Sets file path for the bend table.

The result is required to be a full path, file name and extension to the table to use for the Bend Table.

Mapped network and UNC paths are supported, for example:

"E:\DriveWorks\SheetMetal\Bend Table 2.xlsx"
"\\COMP-NAME\DriveWorks\SheetMetal\Bend Table 2.xlsx"

Base Flange

Parameter	Input Type	Description
Bend Allowance	Number	Sets the value of the bend allowance
Bend Deduction	Number	Sets the value of the bend deduction
Bend Radius	Number	Controls the bend radius for a sheet metal feature
K Factor	Number	Sets the K-Factor
Relief Ratio	Number	Controls the thickness for a sheet metal feature
Thickness	Number	Controls the thickness for a sheet metal feature
Type	One of the following values: Bend Table K Factor Bend Allowance Bend Deduction	Sets the bend allowance type

Break Corner

Parameter	Input Type	Description
Break Type	One of the following values: Fillet Chamfer Corresponding enumeration values can also be used: 0 (for Fillet) 1 (for Chamfer)	Sets the type of break to use.
Distance	Distance in the SOLIDWORKS Document Units.	Sets the chamfer length or fillet radius, depending on the break type.

Parameter

Input Type

Description

Break Type

One of the following values:

Fillet
Chamfer

Corresponding enumeration values can also be used:

0 (for Fillet)
1 (for Chamfer)

Sets the type of break to use.

Distance

Distance in the SOLIDWORKS Document Units.

Sets the chamfer length or fillet radius, depending on the break type.

Edge Flange

Parameter	Type	Description
Auto Relief Type	One of the following values: Obround Rectangle Tear	Sets the auto-relief type for this edge flange. To ensure Auto Relief Type drives correctly please make sure that Custom Relief Type is checked in the master file. CustomReliefTypeSW
Custom Bend Allowance Type	One of the following values: KFactor Bend Table Bend Allowance Bend Deduction	Sets the bend allowance type
Offset DimType	One of the following values: InnerV OuterV BendTangentArc	Sets the offset dimension type for this edge flange
Offset Type	One of the following values: Blind UptoEdgeAndMerge	Sets the offset type for this edge flange
Position Type	One of the following values: BendOutside BendSharp MaterialInside MaterialOutside TangentBend	Sets the Position type for this edge flange
Relief Tear Type	One of the following values: Rip Extend	Sets the type of relief tear for this edge flange feature

Gusset

Parameter	Input Type	Description
Offset Distance	Distance	Set the distance of the offset.
Flip Offset	True/False	Reverses the direction of the offset.
Profile Dimension Scheme	One of the following values: 0 1	Sets the dimension scheme to use. 0 will use the value of the Indent Depth property. 1 will use the values of the Profile Length and Profile Height or Profile Angle properties.
Indent Depth	Distance	Defines a symmetrical gusset profile using a single depth dimension.
Profile Length (d1)	Distance	Specifies a linear value from the inside of the sheet metal part to the point on the x axis where the gusset intersects the sheet metal body.
Use Angle Dimension for Profile	True/False	True to use the Profile Angle parameter, False to use the Profile Height parameter.
Profile Height (d2)	Distance	Specifies a linear value from the inside of the sheet metal part to the point on the y axis where the gusset intersects the sheet metal body.
Profile Angle (a1)	Angle	Creates the section profile of the gusset based on the Profile Length parameter and the angle.
Gusset Type	One of the following values: 0 1	0 creates a gusset with a rounded edge. 1 creates a gusset with a flat edge.
Fillet Gusset Edges	True/False	Gusset Type must be Flat (1). True to apply a fillet to the flat gusset edges.
Edge Fillet Radius	Radius	Gusset Type must be Flat (1). Sets the radius of the flat gusset fillet.
Indent Width	Distance	Sets the gusset width.
Indent Thickness	Distance	Set the wall thickness of the gusset
Draft Side Faces	True/False	True to apply a draft to the gusset.
Draft Angle	Angle	Sets the draft angle to apply to the gusset. Draft Side Faces must be True.
Fillet Inner Corners	True/False	True to set if the inner side of the gusset is filleted.
Inner Corner Fillet Radius	Radius	Sets the radius of the inner corner fillet. Fillet Inner Corners must be True.
Fillet Outer Corners	True/False	True to set if the outer side of the gusset is filleted.
Outer Corner Fillet Radius	Radius	Sets the radius of the outer corner fillet. Fillet Outer Corners must be True.

Jog

Parameter	Input Type	Description
Jog Position	One of the following values: 1 2 3 4	Sets the jog position type for the Jog feature. Select from the following numeric values: 1 = BendCenterLine 2 = MaterialInside 3 = MaterialOutside 4 = BendOutside
Offset Distance	Number	Sets the value of the Jog Offset.
Bend Radius	Number	Sets the bend radius for the Jog feature.
FixProjectedLength	True/False	Sets whether to fix the projected length for the Jog feature.
JogAngle	Number	Sets the jog angle for the Jog feature.
Reverse Direction	True/False	Sets whether to reverse the direction of the Jog feature.
Reverse Offset	True/False	Sets whether to reverse the offset of the Jog feature.
Use Default Bend Allowance	True/False	Sets whether to use the default bend allowance for the Jog feature.
Use Default Bend Radius	True/False	Sets whether to use the default bend radius for the Jog feature.

Miter Flange

Parameter	Input Type	Description
Bend Allowance	Distance	Sets the value of the bend allowance.
Bend Deduction	Distance	Sets the value of the bend deduction.
Bend Radius	Distance	Sets the bend radius of the miter flange. Ensure Use Default Radius is set to False in the master model before you drive the bend radius.
Custom Bend Allowance Type	One of the following values: KFactor Bend Allowance Bend Deduction Corresponding enumeration values can also be used: 2 (for KFactor) 3 (for Bend Allowance) 4 (for Bend Deduction)	Sets the bend allowance type.
End Offset	Distance	Sets the end offset for the miter flange.
Gap Distance	Distance	Sets the gap distance of the tear for the miter flange feature.
K Factor	Double	Sets the K Factor.
Position Type	One of the following values: MaterialInside MaterialOutside BendOutside Corresponding enumeration values can also be used: 1 (for MaterialInside) 2 (for MaterialOutside) 3 (for BendOutside)	Sets the Position type for the miter flange.
Relief Depth	Distance	Sets the relief depth of the miter flange.
Relief Ratio	Double	Sets the relief ratio for the miter flange.
Relief Width	Distance	Sets the width of the relief for the miter flange.
Relief Type	One of the following values: Rectangle Tear Obround Corresponding enumeration values can also be used: 1 (for Rectangle) 2 (for Tear) 3 (for Obround)	Sets the type of relief for the miter flange feature.
Start Offset	Distance	Sets the start offset for the miter flange.
Use Default Bend Allowance	True/False	Sets whether to use the default bend allowance for the miter flange.
Use Relief Ratio	True/False	Sets the Use Relief Ratio for the miter flange.
Use Default Bend Relief	True/False	Sets the Use Default Bend Relief for the miter flange.
Use Position Trim Side Bends	True/False	Sets the Use Trim Side Bends for the miter flange.

Sketched Bend

Parameter	Input Type	Description
FlangePositionTypes	One of the following values: CenterLine BendOutside MaterialInside MaterialOutside	Sets the flange position type of the sketched bend feature
BendAngle	Angle	Sets the bend angle of the sketched bend feature
ReverseDirection	True/False	Sets whether the direction of the sketched bend is reversed
BendRadius	Distance	Sets the bend radius of this sketched bend feature
UseDefaultBendAllowance	True/False	Sets whether to use the default bend allowance for this sketched bend feature
PositionType	FlangePositionTypes	Sets the position of this sketched bend feature
BendAllowance	Distance	Sets the value of the bend allowance
BendDeduction	Distance	Sets the value of the bend deduction
KFactor	Double	Sets the K-factor

Swept Flange

Parameter	Input Type	Description
Bend Allowance	Distance	Sets the value of the bend allowance
Bend Deduction	Distance	Sets the value of bend deduction
Bend Radius	Distance	Sets the bend radius of the swept flange
Custom Bend Allowance Type	One of the following values Bend Table Bend Allowance Bend Deduction KFactor	Sets the bend allowance type
End Offset	Distance	Sets the end offset distance for this swept flange
Flange Position	One of the following values BendOutside MaterialInside MaterialOutside	Sets the flange position type for this swept flange
K Factor	Double	Sets the K-Factor
Relief Depth	Distance	Sets the relief depth of the edge flange
Relief Ratio	Double	Sets the relief ratio for this swept flange
Relief Width	Distance	Sets the width of the relief for this swept flange
Relief Type	One of the following values Obround Rectangle Tear	Sets the type of relief tear for this swept flange feature
Start Offset	Distance	Sets the start offset distance for this swept flange
Use Default Bend Allowance	True/False	Sets whether to use the default bend allowance for this swept flange
Use Default Bend Relief	True/False	Sets the Use Default Bend Relief for this swept flange
Use Default Radius	True/False	Sets whether to use the default bend allowance for this swept flange
Use Position Trim Side Bends	True/False	Sets the Use Trim Side Bends for this swept flange
Use Relief Ratio	True/False	Sets the Use Relief Ratio for this swept flange

DriveWorks Pro 22 Sheet Metal Features