DriveWorks Pro 16: Create Concentric Mate [send feedback...]

Create Concentric Mate - SOLIDWORKS PowerPack

The Create Concentric Mate Generation Task will create a Concentric Mate, in an Assembly, between two Components using a named Face in a Model or an Axis.

This Generation Task does require named faces to exist in the models being mated. Edges or planes cannot be used.
See How to Name and Write Rules for a Face or Plane in a SOLIDWORKS Part for more information about Naming and Writing Rules.

Properties

Property NameDescription
(Name)The unique name for this task.
AlignedThe alignment type (TRUE = Aligned, FALSE = Anti-Aligned)
Lock RotationLocks the rotation (TRUE = Locked, FALSE = Not Locked). The default is FALSE
Position OnlyDoes not apply the mate (TRUE = Position Only, FALSE = Apply Mate). The default is FALSE
First ReferenceThe name of the first reference mating face or axis
First Reference TypeThe type of the first reference (Axis, Named Face)
Second ReferenceThe name of the second reference mating face or axis
Second Reference TypeThe type of the second reference (Axis, Named Face)

Example

When this task is added the properties are both static and dynamic by default.
See How To: Change A Static Property To A Dynamic Property to enable rules to be built on these properties.

Property NameExample RuleExample ResultMeaning
AlignedTRUETRUETRUE set Alignment type to Aligned. FALSE would set this to Anti-Aligned.
Lock RotationTRUETRUETRUE will Lock the Rotations not allowing the Component to rotate. FALSE will allow the Component to rotate.
Position OnlyFALSEFALSEFALSE will apply the Mate. Making this property TRUE will just place the Components but will not Mate them.
First Reference"RunningFace@Axle "&DWSpecificationId&"-1"RunningFace@Axle 9999-1The Name of the first reference Mating Face or Axis.
First Reference TypeNamed FaceNamed FaceNamed Face is the type of reference. Choice of Named Face or Axis.
Second Reference"CentralAxis@Bracket "&DWSpecificationId&"-1"CentralAxis@Bracket 9999-1The Name of the second reference Mating Face or Axis.
Second Reference TypeAxisAxisAxis is the type of reference. Choice of Named Face or Axis.
Rules for faces

When building the rule for the face names, they must reference the generated file name and not the master. The rule must be built in the form: [Face Name]@[Generated model name]-[Instance number]

The rule must include the instance number, even if there is only one instance of the component in the assembly.

Mating planes can only be one level deep. For example, the rule: [Face Name]@[Generated model name]@[Generated sub assembly name] would not be valid.

When filling out the Entity Names it is important to remember to add a space after the end of your model name before your quote otherwise the task will not work. For example "Part "&DWSpecificationId .
For more information about Mate Alignment see Mate Alignment in the SOLIDWORKS Help file.

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Insert Component Generation Task

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